turn on suggestions

Auto-suggest helps you quickly narrow down your search results by suggesting possible matches as you type.

Showing results for

- Navigation
- Simcenter
- Forums
- Blogs
- Knowledge Bases

- Siemens PLM Community
- Simcenter
- 3D Simulation - NX Nastran Forum
- Random response analysis

Options

- Subscribe to RSS Feed
- Mark Topic as New
- Mark Topic as Read
- Float this Topic for Current User
- Bookmark
- Subscribe
- Printer Friendly Page

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Highlight
- Email to a Friend
- Report Inappropriate Content

02-13-2008 04:14 AM

Hello,

I'm looking for someone expert in random response analysis for help, since Nastran

and Femap guides are not very explicative. I try to list some doubts:

-I apply an acceleration load on 4 nodes with a PSD input (in g^2/Hz) with a model

in SI units. When I ask as output acceleration I expect to get again g^2/Hz, right?

And for displacements, forces and stresses which units do I get?

-Is it possible in some way to have a Von Mises stress as output from a random analysis?

-I was asked to calculate differential displacement output between 2 nodes as PSD

by random analysis: is there any way to do that? Is it possible to simply subtract

2 PSD displacement curves (taking absolute value)?

Thanks a lot, and any reference to tutorials or guides is helpful.

Marco

3 REPLIES

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Highlight
- Email to a Friend
- Report Inappropriate Content

02-17-2008 08:40 PM

Hello Marco,

Here are responses to your questions

- I do not recommend that you input your acceleration in units of g^2/Hz. Nastran

does not have the understanding of units and all input has to be in a consistent

unit set. Therefore if you are working in SI units, the acceleration should be defined

in (m/sec^2)^2/Hz. Then all other responses come out in their correct SI units.

I understand that it is more convenient to enter the table in g units. So if you

really want to do that, you should use the scale factor on the RANDPS card to handle

the units conversion. For example if this is your base excitation

Freq (Hz) Accel g^2/Hz

20 5.

50 100.

500 100

2000 5

Then using the conversion that 1 g^2 = 9.8^2 m/sec^2 = 96.04 m/sec^2, you can enter

the TABRAND1 card with values of g^2/Hz and use the scale factor of 96.04 on the

RANDPS card that makes the input in terms of m/sec^2. See the cards below.

RANDPS, 100, 1, 1, 96.04, 0.0, 122

TABRND1, 122, LINEAR, LINEAR, , , , , ,+

+, 20.0, 5., 50.0, 100., 500.0, 100., 2000.0, 5.,+

+, ENDT

The resulting responses, including acceleation will be in SI units. Therefore if

you want acceleation to be in g, you will need to do a conversion. If you are using

NX software, it can do the conversion for you automatically when you are plotting

acceleation. I am not sure what Femap does.

- It is not possible with NX Nastran to compute Von Mises stress for PSD. We are

considering an enhancement for NXN 7 that will compute RMS von mises stress for

PSD. If you are familiar with the NX Response Simulation product - it can compute

RMS von mises and we would use the same method in NXN.

- I think the easiest way to compute the diffential displacement is to use an MPC

equation. Create a dummy node, say node 3, and use it to define the relative x displacement

between node 1 and node 2 by the equation x3 = x2 - x1. In MPC cards this is created

as:

MPC, 100, 3, 1, 1., 1, 1, 1.,+

+, 2, 1, -1.

You can do the same for the y and z directions.

Regards

Mark

"Marco"

>

>Hello,

>I'm looking for someone expert in random response analysis for help, since

>Nastran

>and Femap guides are not very explicative. I try to list some doubts:

>

>-I apply an acceleration load on 4 nodes with a PSD input (in g^2/Hz) with

>a model

>in SI units. When I ask as output acceleration I expect to get again g^2/Hz,

>right?

>And for displacements, forces and stresses which units do I get?

>

>-Is it possible in some way to have a Von Mises stress as output from a random

>analysis?

>

>-I was asked to calculate differential displacement output between 2 nodes

>as PSD

>by random analysis: is there any way to do that? Is it possible to simply

>subtract

>2 PSD displacement curves (taking absolute value)?

>

>Thanks a lot, and any reference to tutorials or guides is helpful.

>

>Marco

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Highlight
- Email to a Friend
- Report Inappropriate Content

02-18-2008 08:38 AM

Hello Mark,

thanks for your help! Now I understand better the situation. I tried MPC method

for relative disps, although results are not exactly as I expected them, because

far from resonance relative disps should be very little, but they aren't... anyway

at least I have a result to work on.

Thanks again

Marco

"Mark Donley"

>

>Hello Marco,

>

>Here are responses to your questions

>

>

>- I do not recommend that you input your acceleration in units of g^2/Hz.

>Nastran

>does not have the understanding of units and all input has to be in a consistent

>unit set. Therefore if you are working in SI units, the acceleration should

>be defined

>in (m/sec^2)^2/Hz. Then all other responses come out in their correct SI units.

>

>I understand that it is more convenient to enter the table in g units. So

>if you

>really want to do that, you should use the scale factor on the RANDPS card

>to handle

>the units conversion. For example if this is your base excitation

>

>Freq (Hz) Accel g^2/Hz

>20 5.

>50 100.

>500 100

>2000 5

>

>Then using the conversion that 1 g^2 = 9.8^2 m/sec^2 = 96.04 m/sec^2, you

>can enter

>the TABRAND1 card with values of g^2/Hz and use the scale factor of 96.04

>on the

>RANDPS card that makes the input in terms of m/sec^2. See the cards below.

>

>RANDPS, 100, 1, 1, 96.04, 0.0, 122

>

>TABRND1, 122, LINEAR, LINEAR, , , , , ,+

>

>+, 20.0, 5., 50.0, 100., 500.0, 100., 2000.0, 5.,+

>

>+, ENDT

>

>

>

>The resulting responses, including acceleation will be in SI units. Therefore

>if

>you want acceleation to be in g, you will need to do a conversion. If you

>are using

>NX software, it can do the conversion for you automatically when you are plotting

>acceleation. I am not sure what Femap does.

>

>

>- It is not possible with NX Nastran to compute Von Mises stress for PSD.

>We are

>considering an enhancement for NXN 7 that will compute RMS von mises stress

>for

>PSD. If you are familiar with the NX Response Simulation product - it can

>compute

>RMS von mises and we would use the same method in NXN.

>

>- I think the easiest way to compute the diffential displacement is to use

>an MPC

>equation. Create a dummy node, say node 3, and use it to define the relative

>x displacement

>between node 1 and node 2 by the equation x3 = x2 - x1. In MPC cards this

>is created

>as:

>

>

>MPC, 100, 3, 1, 1., 1, 1, 1.,+

>+, 2, 1, -1.

>

>You can do the same for the y and z directions.

>

>

>Regards

>Mark

>

>

>

>

>

>

>

>

>

>

>

>

>

>

>"Marco"

>>

>>Hello,

>>I'm looking for someone expert in random response analysis for help, since

>>Nastran

>>and Femap guides are not very explicative. I try to list some doubts:

>>

>>-I apply an acceleration load on 4 nodes with a PSD input (in g^2/Hz) with

>>a model

>>in SI units. When I ask as output acceleration I expect to get again g^2/Hz,

>>right?

>>And for displacements, forces and stresses which units do I get?

>>

>>-Is it possible in some way to have a Von Mises stress as output from a random

>>analysis?

>>

>>-I was asked to calculate differential displacement output between 2 nodes

>>as PSD

>>by random analysis: is there any way to do that? Is it possible to simply

>>subtract

>>2 PSD displacement curves (taking absolute value)?

>>

>>Thanks a lot, and any reference to tutorials or guides is helpful.

>>

>>Marco

>

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Highlight
- Email to a Friend
- Report Inappropriate Content

02-18-2008 08:59 AM

Marco,

I am not sure what the relative displacement should be for your model. But if you

are using the default enforced motion method NASTRAN SYSTEM(422)=1, then you must

remember to use residual vectors PARAM, RESVEC, YES. This could make a difference

in what you are seeing.

Mark

"Marco"

>

>Hello Mark,

>

>thanks for your help! Now I understand better the situation. I tried MPC method

>for relative disps, although results are not exactly as I expected them, because

>far from resonance relative disps should be very little, but they aren't...

>anyway

>at least I have a result to work on.

>

>Thanks again

>

>Marco

>

>"Mark Donley"

>>

>>Hello Marco,

>>

>>Here are responses to your questions

>>

>>

>>- I do not recommend that you input your acceleration in units of g^2/Hz.

>>Nastran

>>does not have the understanding of units and all input has to be in a consistent

>>unit set. Therefore if you are working in SI units, the acceleration should

>>be defined

>>in (m/sec^2)^2/Hz. Then all other responses come out in their correct SI

>units.

>>

>>I understand that it is more convenient to enter the table in g units. So

>>if you

>>really want to do that, you should use the scale factor on the RANDPS card

>>to handle

>>the units conversion. For example if this is your base excitation

>>

>>Freq (Hz) Accel g^2/Hz

>>20 5.

>>50 100.

>>500 100

>>2000 5

>>

>>Then using the conversion that 1 g^2 = 9.8^2 m/sec^2 = 96.04 m/sec^2, you

>>can enter

>>the TABRAND1 card with values of g^2/Hz and use the scale factor of 96.04

>>on the

>>RANDPS card that makes the input in terms of m/sec^2. See the cards below.

>>

>>RANDPS, 100, 1, 1, 96.04, 0.0, 122

>>

>>TABRND1, 122, LINEAR, LINEAR, , , , , ,+

>>

>>+, 20.0, 5., 50.0, 100., 500.0, 100., 2000.0, 5.,+

>>

>>+, ENDT

>>

>>

>>

>>The resulting responses, including acceleation will be in SI units. Therefore

>>if

>>you want acceleation to be in g, you will need to do a conversion. If you

>>are using

>>NX software, it can do the conversion for you automatically when you are

>plotting

>>acceleation. I am not sure what Femap does.

>>

>>

>>- It is not possible with NX Nastran to compute Von Mises stress for PSD.

>>We are

>>considering an enhancement for NXN 7 that will compute RMS von mises stress

>>for

>>PSD. If you are familiar with the NX Response Simulation product - it can

>>compute

>>RMS von mises and we would use the same method in NXN.

>>

>>- I think the easiest way to compute the diffential displacement is to use

>>an MPC

>>equation. Create a dummy node, say node 3, and use it to define the relative

>>x displacement

>>between node 1 and node 2 by the equation x3 = x2 - x1. In MPC cards this

>>is created

>>as:

>>

>>

>>MPC, 100, 3, 1, 1., 1, 1, 1.,+

>>+, 2, 1, -1.

>>

>>You can do the same for the y and z directions.

>>

>>

>>Regards

>>Mark

>>

>>

>>

>>

>>

>>

>>

>>

>>

>>

>>

>>

>>

>>

>>"Marco"

>>>

>>>Hello,

>>>I'm looking for someone expert in random response analysis for help, since

>>>Nastran

>>>and Femap guides are not very explicative. I try to list some doubts:

>>>

>>>-I apply an acceleration load on 4 nodes with a PSD input (in g^2/Hz) with

>>>a model

>>>in SI units. When I ask as output acceleration I expect to get again g^2/Hz,

>>>right?

>>>And for displacements, forces and stresses which units do I get?

>>>

>>>-Is it possible in some way to have a Von Mises stress as output from a

>random

>>>analysis?

>>>

>>>-I was asked to calculate differential displacement output between 2 nodes

>>>as PSD

>>>by random analysis: is there any way to do that? Is it possible to simply

>>>subtract

>>>2 PSD displacement curves (taking absolute value)?

>>>

>>>Thanks a lot, and any reference to tutorials or guides is helpful.

>>>

>>>Marco

>>

>

Follow Siemens PLM Software

© 2017 Siemens Product Lifecycle Management Software Inc