turn on suggestions

Auto-suggest helps you quickly narrow down your search results by suggesting possible matches as you type.

Showing results for

- Navigation
- Simcenter
- Forums
- Blogs
- Knowledge Bases

- Siemens PLM Community
- Simcenter
- CAE Simulation - Femap Forum
- Material Stress-Strain Data question in Nonlinear ...

Options

- Subscribe to RSS Feed
- Mark Topic as New
- Mark Topic as Read
- Float this Topic for Current User
- Bookmark
- Subscribe
- Printer Friendly Page

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Permalink
- Email to a Friend
- Report Inappropriate Content

06-26-2016 04:06 PM

A kinda basic question regarding which material stress-strain data to use in Non-linear analysis.

If I choose Plastic Option in the Material -> Non-linear tab and want to associate a function as shown below:

Does the function can be a:

- Engineering Stress-Strain Curve
- True Stress vs Plastic Strain

The question applies to SOL 106 & 601 as well. The understanding I have is that for SOL 106, engineering stress-strain curve can be used but for SOL 601, a true stress vs plastic strain is needed?

3 REPLIES

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Permalink
- Email to a Friend
- Report Inappropriate Content

06-27-2016 04:54 AM

Dear Nagaraj,

**•** With **NX NASTRAN Basic Nonlinear (SOL106)** the first type of nonlinear isotropic material is the NonLinear Elastic material (**MATS1, TYPE=NLELAST**). This material does not exhibit strain hardening or as the load is released on the material, the material simply releases it’s strain based on the strain vs. stress curve selected in the **Function Dependence** property. The function for nonlinear elastic materials should be defined in the first and third quadrants to accommodate different uniaxial tension and compression properties. Nonlinear elastic properties can only be defined for isotropic materials. It is important to note that the Femap function must be of the type "**4..vs. Stress**" as opposed to the more familiar Stress vs. Strain curve.

**•** The second nonlinear model of NX NASTRAN (SOL106) is the bi-linear **Elasto-plastic **curve: this material do exhibit strain hardening, it can also include mixed Isotropic+Kinematic hardening definitions. The Elasto-plastics material model can be used with any combination of small or large displacements and small or large strains. Elasto-plastic materials use the linear constants EX coupled with the plasticity modulus, H to define a bi-linear stress-strain curve with the work hardening slope, and is related to the tangential modulus, ET (the slope of stress vs. plastic strain).

The Yield Criterion option contains information on the yield types to be used. This box is only relevant for elasto-plastic and plastic nonlinearity types. Four yield criterion are available (**von Mises, Tresca, Mohr-Coulomb, and Drucker-Prager**). Von Mises and Tresca require input of the initial yield stress, while Mohr-Coulomb and Drucker-Prager require input of 2*cohesion and angle of internal friction.

• The final type of nonlinear isotropic model is the **Multilinear Plastic material ( MATS1, TYPE=PLASTIC)**. To specify this type of material, you specify an Initial Yield Stress, the Yield Criterion, and under FUNCTION DEPENDENCE the "

Please note:

- For NX NASTRAN (SOL106) the solver supports only engineering stress-strain curves.
- The module NX NASTRAN Advanced Nonlinear Solver (SOL601) allows to convert "
**engineering stress - strain**" values to "" values using the__true__stress - strain**CSVSSVAL**parameter (note: CVSSVAL is only applicable for the multilinear-plastic material model).

Best regards,

Blas.

Blas Molero Hidalgo, Ingeniero Industrial, Director

IBERISA • 48004 BILBAO (SPAIN)

WEB: http://www.iberisa.com

Blog Femap-NX Nastran: http://iberisa.wordpress.com/

IBERISA • 48004 BILBAO (SPAIN)

WEB: http://www.iberisa.com

Blog Femap-NX Nastran: http://iberisa.wordpress.com/

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Permalink
- Email to a Friend
- Report Inappropriate Content

06-28-2016 12:45 AM

Thank you for the clarification.

So, I gather that for SOL 601, if I want to capture Plasticity effects accurately, I can create an engineering stress-strain function and ask the solver to convert it in to true stess-strain function using the **CSVSSVAL **parameter.

From your experience, is it recommended to use true stress-strain values for most engineering applications or just use engineering stress-strain values?

Again, per my understanding, true values are recommended if the intent is to capture response up to failure (like modeling the response of a test specimen etc) and engineering values are sufficient to find out response of the structure beyond elastic domain (not necessarily that the stress values may reach Ftu in the component).

Does the above makes sense?

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Permalink
- Email to a Friend
- Report Inappropriate Content

06-29-2016 05:02 AM

Hello!,

- When the stress is calculated on the basis of the original area, it is called the
**Engineering or Nominal Stress**. The same way, if the original length is used to calculate the strain, then it is called the**Engineering Strain**. - If the stress is calculated based on the instaneous area at any instant of load, then it is the
**True Stress**. Similarly,**True strain**. - Engineering stress-strain diagrams are usually used in the elastic range, while True stress – strain diagrams are used in plastic range.
- Most of the diagram used for practical purposes are based on engineering stress vs. engineering strain, while true stress – true strain diagrams are required occasionally.

In practice, it is noteworthy to mention that the true stress-strain are basically indistinguishable from the engineering stress-strain at small deformations. To learn more about the diferences between NX Nastran Basic Nonlinear (SOL106) and Advanced Nonlinear (SOL601) take a look to this document from Chip Frickle, all is written there, thanks Chip!!: http://www.iberisa.com/transfer/Femap-BasicNonlinear-AdvanceNonlinear.zip

Best regards,

Blas.

Blas.

Blas Molero Hidalgo, Ingeniero Industrial, Director

IBERISA • 48004 BILBAO (SPAIN)

WEB: http://www.iberisa.com

Blog Femap-NX Nastran: http://iberisa.wordpress.com/

IBERISA • 48004 BILBAO (SPAIN)

WEB: http://www.iberisa.com

Blog Femap-NX Nastran: http://iberisa.wordpress.com/

Follow Siemens PLM Software

© 2018 Siemens Product Lifecycle Management Software Inc