Auto-suggest helps you quickly narrow down your search results by suggesting possible matches as you type.

Showing results for

- Navigation
- Simcenter
- Forums
- Blogs
- Knowledge Bases

- Siemens PLM Community
- Simcenter
- CAE Simulation - Femap Forum
- Simulating Spring with variable Stiffness

Options

- Subscribe to RSS Feed
- Mark Topic as New
- Mark Topic as Read
- Float this Topic for Current User
- Bookmark
- Subscribe
- Printer Friendly Page

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Permalink
- Email to a Friend
- Report Inappropriate Content

10-19-2015 03:54 AM

Hi everyone,

I would like to simulate Spring in my model with variable stiffness. I have a Force/Displacement diagramm. How can I make it with SOL101?

Best regards,

Peter Kaderasz

Solved! Go to Solution.

8 REPLIES

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Permalink
- Email to a Friend
- Report Inappropriate Content

10-20-2015 08:15 AM

Hi,

You can use CBUSH elements. Create a PBUSH and you will be able to directly use the Force/Displacement diagram you have created under functions.

Go to Nonlinear/Freq Resp / Nonlinear Function Dependence. You can vary the stiffeness for each DOF independently:

Seifeddine Naffoussi

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Permalink
- Email to a Friend
- Report Inappropriate Content

10-20-2015 11:54 AM

Hi SN,

where can I find Force vs. Displacement function in Femap? When I use **0..Dimensionless** function and write 1 to Stiffness, Femap always calculate with Stiffness value equal to Y value at X=1. In this case Stiffness didn't depend on Force value in my Load Set. This happenned with Analysis type **10..Nonlinear Static**.

I would like to use Stiffness from Force/Displacement diagram in my analysis.

Best regards,

Peter Kaderasz

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Permalink
- Email to a Friend
- Report Inappropriate Content

10-29-2015 03:30 AM

Hi Peter,

I see from your posts that you have figured out that you must use non-linear analysis (not SOL101) in order to use a force-displacement function for a bush.

Note that various Function types will work (Dimensionless, Force vs Frequency, Displacement vs Frequency (!!), Stress vs Frequency. All of these produce the same effect in the Nastran .dat file, writing the required PBUSHT and TABLED1 entries. Note that the X in your function is displacement, and Y in your function is force. However, for you to see non-linear effects, you need to carefully choose the pairs of force and displacement values in the function and calculate intermediate results which traverse** gradient **changes in the force-displacement function.

Regards,

EndZ

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Permalink
- Email to a Friend
- Report Inappropriate Content

11-02-2015 06:02 AM

Hi Endz,

I made a model to testing Spring with variable Stiffness. Here is my Spring property:

Here is my function:

I launched a nonlinear analysis:

The resultat was with F=25 N the following:

Displacement of Node 51 was 25 mm, this means, that the Stiffness was 1 N/mm. I tested with lot of forces, but the stiffness was always 1 N/mm, the model didn't use the function.

What's wrong with my model?

Best regards,

Peter Kaderasz

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Permalink
- Email to a Friend
- Report Inappropriate Content

11-02-2015 07:39 AM

Hi,

Could you put the .dat file ? I will take a look.

Seifeddine Naffoussi

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Permalink
- Email to a Friend
- Report Inappropriate Content

11-02-2015 07:48 AM

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Permalink
- Email to a Friend
- Report Inappropriate Content

11-02-2015 08:47 AM

The nastran element force sign convention is causing your spring to be in compression, while your force displacement curve is always positive. Notice in your f06 file, the messages about table lookup erros, nastran is trying to look up negative values which do not exist so it is extrapolating on the negative side of your curve which is always 1.

On your spring entry, reverse the order of the nodes.

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Permalink
- Email to a Friend
- Report Inappropriate Content

11-02-2015 09:02 AM

Thank you.

Follow Siemens PLM Software

© 2018 Siemens Product Lifecycle Management Software Inc