Turn on suggestions

Auto-suggest helps you quickly narrow down your search results by suggesting possible matches as you type.

Showing results for

- Navigation
- Simcenter
- Forums
- Blogs
- Knowledge Bases

- Siemens PLM Community
- Simcenter
- CAE Simulation - Simcenter Nastran Forum
- Spring elements that only work in compression

Options

- Start Article
- Subscribe to RSS Feed
- Mark Topic as New
- Mark Topic as Read
- Float this Topic for Current User
- Bookmark
- Subscribe
- Printer Friendly Page

Spring elements that only work in compression

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Permalink
- Email to a Friend
- Report Inappropriate Content

10-17-2018 05:42 PM

Hi All,

I am looking for an option to simulate springs that do not resist in tension and only resist in compression. I prefer a linear solution not a contact to solve this problem.

Thanks,

Labels:

1 REPLY 1

Re: Spring elements that only work in compression

- Mark as New
- Bookmark
- Subscribe
- Subscribe to RSS Feed
- Permalink
- Email to a Friend
- Report Inappropriate Content

10-17-2018 06:16 PM

By definition, a variable stiffness spring is not linear (i.e. nonlinear).

The CGAP element is a bilinear stiffness spring - you define an open and closed stiffness on PGAP

In SOL 101, the element by default is treated as linear (only one of the stiffness values is selected based on the initial open/closed status and that stiffness is used for the duration of the solution). If you include a BCSET case control, the CGAP will be treated as contact and will essentially be compression only. See Including CGAP Elements in a Contact Solution in the online help.

In SOL 106, the CGAP is truly a nonlinear spring. The solution checks the open/closed status every increment and switches between the open/closed stiffness as required. This is exactly what you are asking for. If you have no other material nonliearities defines and PARAM, LGDISP is set to -1, the solution will essentially be linear except for the cgap iterations.

There are other nonlinear options as well. in SOL 401, CBUSH stiffness can be made nonlinear by providing KN values on PBUSHT. Again, a nonlinear solution is required, but if there are no other nonliearities defined, the only nonlinear aspect will be the PBUSHT.

Follow Siemens PLM Software

© 2019 Siemens Product Lifecycle Management Software Inc