I am studying how to calculate normal mode with Surface to Surface Contact condition applied.
My model has two flat plates connected by spot welding as shown in the Figure 1 .
If there is no STS Contact condition, the first natural frequency is 25.8 Hz.(Figure 2)
If there is STS Contact condition But the gravity is not applied, the first natural frequency is 34.8 Hz.(Figure 3)
If STS Contact and gravity are applied, the first natural frequency is 120.3 Hz.(Figure 4)
if Gravity is not applied , the distribution of the contact pressure is very strange.(Figure 5)
My question is as below...
1. Why do I have so many different natural frequencies with and without gravity?
2. Assuming that applying gravity is a better condition, the natural frequency is too high when applying STS Contact conditions.(This results is not realistic...)
How can i get more realistic results?....
3.If the STS Contact condition is applied , the plates are attached and moves together like Glue condition..
How do I get the same mode shape that Blas Molero (https://iberisa.wordpress.com/2011/11/07/analisis-de-frecuencias-sol103-de-un-ensamblaje-con-contact...) did?
(i.e. No penetration but not attached during mode shape animation)
Is it possible with Sol103?
I attached fem and sim file and please let me know if i had imposed an inappropriate conditions.
Any answers will be very helpful.
The animations on the web page you reference are deceiving because the video only shows 0 to max displacement (a Linear animation in Simcenter terminology). To see the full mode shape, the author should have used a Modal animation (-max to max). This is why you are not seeing penetration in the Mode#3 = 2377.522 Hz animation.
Here is the linear animation:
And here is the corresponding modal animation:
A couple of issues particular to your model:
The equation shown shows how the initial contact condition is created. During the solution, the solver iterations will deactivate contact elements that have separated or have no normal force in them. So, even though contact is initially set up as you describe, at the end of the static subcase, most or all of the contact elements will be inactive if there is no load or interference in the model.