cancel
Showing results for 
Search instead for 
Did you mean: 

How to change Simulate Tool position on the machine configurator?

Solution Partner Creator Solution Partner Creator
Solution Partner Creator

Hi,
i`m working on 5axis machine simulate customize.
controllor is iTNC530 and i have a question of Machine configurator.

 

The "cycl def 7" command value is fixed "0".
And when i start machine code simulate, tool position is not matched on Local MCS.
I can understand why this happening.

 

Now is Question.
Keep above this condition(about cycl def 7 command value),
How to change simulate tool position about on the Machine configurator?

 

Machine Zero position is Spindle head point.
MCS Position is on the part.
If you are need more information, i`ll give you another information.

6 REPLIES

Re: How to change Simulate Tool position on the machine configurator?

Esteemed Contributor
Esteemed Contributor

If your MCS has the "Fixture Offset" value set to zero, then your machine simulation is based on the machine zero.

If you need it based on a different preset, then you need to change the value to 1 or above depending on the preset you use on the machine.

Stefan Pendl, Systemmanager CAx, HAIDLMAIR GmbH
Production: NX10.0.3, VERICUT 8.0, FBM, MRL 3.1.4 | TcUA 10.1 MP7 Patch 0 (10.1.7.0) | TcVis 10.1
Development: VB.NET, Tcl/Tk    Testing: NX12.0

How to Get the Most from Your Signature in the Community

Re: How to change Simulate Tool position on the machine configurator?

Solution Partner Creator Solution Partner Creator
Solution Partner Creator

Hi, Stefan.

 

See this situation.

Tool position is wrong.

I want to tool position is matched Part location.

Fixed RED BOXFixed RED BOX

 

Machine zero positionMachine zero position

How can i solve this problem??

help please.

Re: How to change Simulate Tool position on the machine configurator?

Siemens Phenom Siemens Phenom
Siemens Phenom

#### update ###

 

sorry its not related to tool change ;-)

 

####

 

Hi,

 

the values for the tool change position itself can easily configured (without Machine Configurator) within the toolchange subprogram. Look at the marked lines

 

2017-06-28 09_18_11-Program Manager.jpg

 

 

If CYCL DEF 7 is called before the toolchange starts and there are offsets included then the tool change positions are depending on that offset.

 

Normally the tool change position is on a fixed position in machine coordinate system and independent of any local work offsets. 

 

Thomas

Re: How to change Simulate Tool position on the machine configurator?

Siemens Phenom Siemens Phenom
Siemens Phenom

Please verify the following points:

- Move to machine zero position with L X0 Y0 Z0 without a tool --> works as expected?
- Move to machine zero position with L X0 Y0 Z0 with a tool and activated tool length compensation --> works as expected?
- verify M128 

  • mount a tool
  • activate tool length compensation
  • Activate M128
  • Move to machine zero position with L X0 Y0 Z0
  • Rotate axis B or C to any value
  • --> stays the tool tip on a fixed position?

 

Thomas

Re: How to change Simulate Tool position on the machine configurator?

Esteemed Contributor
Esteemed Contributor

How is your geometry view setup in the ONT?

Ours is as shown below, where we have the main machine zero at the very top, blow some workpiece groups and below those the corresponding fixture offsets.ONT Geometry ViewONT Geometry View

 

 

Main Machine Zero MCSMain Machine Zero MCS

 

 

1st Fixture Offset MCS1st Fixture Offset MCS

 If you do not have a fixture offset with any number other than zero defined for the operation you are simulating, then the NC code simulation will be done based on the machine zero.

Stefan Pendl, Systemmanager CAx, HAIDLMAIR GmbH
Production: NX10.0.3, VERICUT 8.0, FBM, MRL 3.1.4 | TcUA 10.1 MP7 Patch 0 (10.1.7.0) | TcVis 10.1
Development: VB.NET, Tcl/Tk    Testing: NX12.0

How to Get the Most from Your Signature in the Community

Re: How to change Simulate Tool position on the machine configurator?

Genius
Genius
Hello,

I see you have defined the Main MCS in the Machine Zero Junction and an Local MCS on the part.
In the NC Code there are
CYCL DEF 7.0 DATUM SHIFT
CYCL DEF 7.1 X=0
CYCL DEF 7.2 Y=0
CYCL DEF 7.3 Z=0

You have to define here the real Values from Main MCS to Local MCS
CYCL DEF 7.0 DATUM SHIFT
CYCL DEF 7.1 X=-100
CYCL DEF 7.2 Y=300
CYCL DEF 7.3 Z=-500

Learn online





Solution Information