Hi! I need Your help!
The first problem is:
I don't know how to multiply the same part and start manufacturing all of them using one piece of blank.Obviously I do know how to multiply object in modeling,I can take one object, do a patern but is there any posible to do this in Manufacturing? Sometimes I have different parts, I don't want to do this manually-I would like to choose a part, give an amount and that's it.
For example: I need ten cylinders d20x2 [mm],blank is 2mm thick.
The second problem is more important to me- How can I make (here I don't know how to call this) bridge/support/this green thing ? I realy need this couse there is a lot of vibrations during the milling process, so these parts can not move. Here is better shot:
Solved! Go to Solution.
Are you asking how to make these tab supports automatically in the operation? That's not a current feature. You will need to model these in CAD and pattern them as you seem to have done already, or create boundaries with curves or points to use in the operation. Depending on the operation type you are using to cut the parts you will need to use either Check Bodies or Check Boundaries.
Does this need to be added to the part model?
Or the blank?
or just as "check" geometry?
Particularly for mill-turns & lathes, I suggest users create a "manufacturing model"
This is an assembly of the engineering part, with the engineering part's solid body WAVE linked in.
Now you have a solid you can modify (add grind stock, or fillets/rounds/chamfers, or whatever - in your case, the green thing)
Then in your CAM (NC program) part, use the manufacturing model as the solid to machine.
Production: NX10.0.3.5 MP16/TC11.2
I'd rather be e-steamed than e-diseaseled
You don't have to unite the bridge with the part you are cutting. Your first example of two different bodies was just fine. When defining your Workpiece in the Geometry View, simply select the round disk as the Part and then select the bridge body as the Check. The tool paths will avoid gouging both bodies, but you can specify different offsets for each. For example, you can rough out the Part (round disk) to 1.0mm full but cut the Check (bridge) to 0.0mm.
If these bridges are supposed to connect the part into the stock to use it as a sort of fixturing then you may need to model that as well and use it as the Check.
Planar Profile should be just fine if you simply want to cut around the part shape. The Check is defined as boundaries rather than a body, but it looks like you have that figured out.
To use the solids rather than boundaries you can try using Zlevel Profile.
May be solid-profile-3D is an option for you too?
The operation you use highly depends on the input you have.
For example, if I want to machine a wall, but the path must follow the floor, I use flowcut multiple.
Production: NX10.0.3, VERICUT 8.2, FBM, MRL 3.1.7 | TcUA 10.1 MP7 Patch 0 (10.1.7.0) | TcVis 11.4
Development: C (ITK), .NET, Tcl/Tk Testing: NX12.0 | AWC 3.4 Preparing: NX12.0
Employees of the customers, together we are strong
How to Get the Most from Your Signature in the Community
NX Customization - Best Practice Guide