02-19-2018 10:16 AM
01. You put the Stock on Wise
02. Machine the Part (TOP Machining)
03. Put the part 180 deg in Wise for Bottom Machining
How many files you have for a Manufacturing Part ?
I mean, do you have one file for TOP machining and another for Bottom Machining
What is the best way to organize the process ?
02-19-2018 10:51 AM
The best way is to have each setup in its own part file. This makes it much easier to do machine simulation of each situation.
If I remember correctly the machining line planer, included since NX 10 at least, should simplify the process of creating multiple setups. There is a video by @TomvantErve in the community.
Production: NX10.0.3, VERICUT 8.2, FBM, MRL 3.1.7 | TcUA 10.1 MP7 Patch 0 (10.1.7.0) | TcVis 11.4
Development: C (ITK), .NET, Tcl/Tk Testing: NX12.0 | AWC 3.4 Preparing: NX12.0
Employees of the customers, together we are strong
How to Get the Most from Your Signature in the Community
NX Customization - Best Practice Guide
02-19-2018 10:53 AM
We do recommend that users make a new file for every machine setup they create. This has a few advantages.
On the other hand, all setups and tool path data can be made in just one file. Mutiple MCS objects can be made for each setup on the part. The operations under each MCS in the Geometry View will be oriented to their parent MCS. This has the obvious advantage of having to manage only one NX part file rather than several files together.
The choice is up to you. Siemens has what we consider to be best practices, but your workflow should dictate what is right for your shop.
02-19-2018 11:53 AM
Thanks all. I am in practice mode ! I am doing this :
- Create TOP file asm : add Part - add wise/clamps - link body all
- Create operation for TOP machining
Now I have a problem.
- When create Bottom file, I want the IPW from Top and I can not bring it to file (NX 11)
- But if I create parasolid of IPW (which I do not want), I have another problem since wise setup from Top it is not good for Bottom !!!
Also, is anywere a Setup in NX to put a clearacnce to "Specify Check". I see the Tool is JUST avoiding it but I would like to put like 1mm clearance to it.
02-19-2018 11:59 AM
Hmmm, I have Manufacturing but I do not have File - New - Manufacturing option !
This is maybe the reason for IPW
02-19-2018 12:01 PM
Edit the Workpiece object in the second setup file. Select the same part geometry as before. Now in the Blank Geometry definition, select the pull-down menu at the top and select IPW - In Process Workpiece.
Now select the Select Source for IPW button and browse for your first setup file. Select the Workpiece object from that file and select OK. Select the Update Local IPW from Source button and you should see a facet model in the graphics. Select OK and the roughing operations will use this to calculate IPW regions.
Let us know if this works.
02-19-2018 01:58 PM
"The part containing the source for IPW must reference the same component for Part geometry as the work part"
02-19-2018 02:08 PM
That is not a problem:
First setup: CAM-Part-Machine-Top | +- CAD-Part Second setup: CAM-Part-Machine-Bottom | +- CAD-Part
You always have the same CAD-part file as the component in each CAM setup part. The fixture, machine, etc. can be different, only the design part must be the same.
Production: NX10.0.3, VERICUT 8.2, FBM, MRL 3.1.7 | TcUA 10.1 MP7 Patch 0 (10.1.7.0) | TcVis 11.4
Development: C (ITK), .NET, Tcl/Tk Testing: NX12.0 | AWC 3.4 Preparing: NX12.0
Employees of the customers, together we are strong
How to Get the Most from Your Signature in the Community
NX Customization - Best Practice Guide
02-19-2018 02:13 PM
Got it, thanks a lot...
02-19-2018 03:47 PM