Our customer sent us a file which was (probably) originally created in Solid Works, then translated into Solid Edge, and finally opened in NX.
The problem is corrupted geometry, which I am trying to modify with Synchronous Modeling commands: Move Face, Delete Face, Move Edge etc. See pic1.
In addition, the body reports a problem when I am trying to use Measure Body. (pic2)
I used Heal Geometry and Optimize Face, but it didn't succeed.
How should I fix the geometry? Please help!
Solved! Go to Solution.
You might find that you have to remove more than you expected to cleanup those faces. For example, try removing the entire blends colored grey using Delete Face. Unfortunately the Synchronous Modeling commands are not quite as straight forward as one would hope in these cases - you may have to get inventive.
Start with the 'examine geometry' command. Turn on all the body and face checks, rectangle select around the entire model, and press OK; this should highlight the problem areas that need attention.
You will probably have to sew, unsew faces, delete face command with heal turned off, then finaly use fill surface command to fill in the open surfaces. You will then need to sew everything back together into a solid body
NX 22.214.171.124 MP11 Rev. A
GM TcE v126.96.36.199
GM GPDL v11-A.3.6
Thank you guys!!! You helped me so much!!!
I made several steps to fix it:
1. I deleted all the blends that didn't cause problems.
2. I copied arc of the problem corner using Composite Curve.
3. Then I unsewed the model using Delete Face with the Heal checkbox off and got a sheet body.
4. In the problem corner I created a surface using Through Curves Mesh on the copied arces, then I sewed the model with this surface. The new solid body became more NX-friendly and I was able to use Delete Face on the problem blend!