When creating a part or an assembly in NX should the detail drawing be a separate file?
1. I know you can change between modeling and drafting under the model file, but doing this doesn't allow use of attributes connected to the title block. (NX-Design-Forum/Numeric-expressions-driven-by-attributes/m-p/519669#M26228)
2. If you create a new file for the drawing associated to the model, you must "add" the model to the drawing file in modeling in order for the template border to update (parts list, attribute name, etc.). However this option doesn't allow you to show the exploded view associated with an assembly.
If you are creating a true "exploded" view, this must be done in the drawing file, NOT the model file.
If you are using an arrangment as the explosion, that should work in either the model or drawing file.
Master Model approach vs. the embedded drawing approach where master model has separate files for the 3D CAD and the 2D drawing and the embedded drawing is, well, embedded and in a single file.
While I prefer the master model approach as it supports concurrent design/drafting, in a native (non-managed) system, it is easier to have a single file that is both the 3D model and the 2D drawing. Fewer files to maintain. A save-as to a new part number is easy.
If you follow the master model approach in a native (non-managed) system, you have to remember that there is a drawing associated with your part and save-as the drawing and the 3D model.
If you're in Teamcenter, the management of the separate files is automatic making it much easier.
I agree, I prefer using the master model approach. I am using Teamcenter, so the management of files is not an issue. It is strange that there is an option though. Shouldn't this be a standard operation? Either a model file contains everything including the drawing, or all files are separate.
I think it's just a matter of Unigraphics providing the option to do it either way, depending on the customer needs. I've worked with master model in Teamcenter (my preference), but also master model in native, and single file in native. All work, just different.
While I prefer master model ("MM") approach, one place that having "everything in one file" seems to work better is for part families, if you want specific drawings for each part family member. I don't know if NX has made any enhancments to support using MM for part families recently, however.
Production: NX10.0.3.5 MP16/TC11.2
I'd rather be e-steamed than e-diseaseled