Cancel
Showing results for 
Search instead for 
Did you mean: 
Highlighted

NX11 - Sheet Metal - Cannot select faces in JOG or JOGGLE functions

Creator
Creator

Hi,

I am building a sheet metal (0.5 mm steel part) product using Sheet Metal module. The model contains some TABS, PUNCHES and I want also to include some JOGGLES. But...for some reason NX does not want to select faces nor lines or edges in JOGGLE function. Nothing is selectable. If I get out the Joggle function, again everything becomes selectable and highligted when I touch. I checked the same issue exists also with BEND and FLANGE functions (i.e. nothing is selectable). Are there any conditions for the faces to be selectable in those functions (i.e. JOGGLE, JOG, BEND, FLANGE)? 

Thanks.

9 REPLIES 9

Re: NX11 - Sheet Metal - Cannot select faces in JOG or JOGGLE functions

Solution Partner Pioneer Solution Partner Pioneer
Solution Partner Pioneer

HI @S_Bachar

 

Please confirm that in your Selection filter (Left Corner)You choose the right content.

OR keep it as "NO Selection" 

or

If ur working in layers You have to check the working layers must be Accurate

Re: NX11 - Sheet Metal - Cannot select faces in JOG or JOGGLE functions

Siemens Phenom Siemens Phenom
Siemens Phenom

Hi @S_Bachar

It does sound like a selection filtering issue if it impacts several commands however each command has a different list.

 

You could try and resetting dialog memory?

2019-01-22 13_44_57-Clipboard.png

 Post some images of what you are seeing may help.

 

Dave

Re: NX11 - Sheet Metal - Cannot select faces in JOG or JOGGLE functions

Phenom
Phenom

@S_Bachar

 

Just a wild guess;

Did you create your base feature with an extrude instead of a Sheet Metal Tab?

I woulnd't be surprised that the model you're trying to apply a Joggle on isn't a valid sheet metal part for that reason.

Do a "convert to sheet metal" and try again. Smiley Wink

 

 

Huysmans Metalen n.v.
2x NX 12.0.2.9 Mach Designer
on Win10 64bit
NX Beta Tester with focus on Sheet Metal
Command Finder is your friend

Re: NX11 - Sheet Metal - Cannot select faces in JOG or JOGGLE functions

Creator
Creator

When I enter the JOGGLE function, I have only the "Face" option in selection list. There is nothing else...And I cannot select any face as I wrote...

Re: NX11 - Sheet Metal - Cannot select faces in JOG or JOGGLE functions

Phenom
Phenom

@S_Bachar

You can also use HD3D tools to check if the body is a valid Sheet Metal body:

2019-01-22_06.pngNX12 HD3D: Sheet Metal Body check

You can also use HD3D to check what type all the body's faces are; that might also be a quick indication for valid/invalid edges.

Huysmans Metalen n.v.
2x NX 12.0.2.9 Mach Designer
on Win10 64bit
NX Beta Tester with focus on Sheet Metal
Command Finder is your friend

Re: NX11 - Sheet Metal - Cannot select faces in JOG or JOGGLE functions

Creator
Creator

You are right! What I did was:

My base part "was" solid. It was a solid tube (large dia with thin thickness), that I cut it and flattened or unbend it (I couldn't find another way to create a tube from (rectangular) sheet plate).

Converted it to sheet metal. 

Added some tabs, punches, etc...

Then I wanted to add some Joggles (which didn't work).

But, should (or can I) convert to sheet metal various times during modelling? I thought once in the beginning was OK...

Re: NX11 - Sheet Metal - Cannot select faces in JOG or JOGGLE functions

Phenom
Phenom

There are many possibilities to "ruin" the validity of a body being sheet metal. Once you break, you can model everything "looking" OK. But still in the background it can be broke.

Then "Convert to Sheet Metal" is your tool. So don't be held back to use it more than once. If you need it, use it. Smiley Very Happy

Huysmans Metalen n.v.
2x NX 12.0.2.9 Mach Designer
on Win10 64bit
NX Beta Tester with focus on Sheet Metal
Command Finder is your friend

Re: NX11 - Sheet Metal - Cannot select faces in JOG or JOGGLE functions

Creator
Creator

Hahaha...Thanks for the tip.

Now it works. You are my hero!

 

P.S. I didn't know that I should and can use the convert to SM tool more than once!

Re: NX11 - Sheet Metal - Cannot select faces in JOG or JOGGLE functions

Siemens Phenom Siemens Phenom
Siemens Phenom

Well done @frank_nx !!

 

Glad you got it sorted @S_Bachar.

 

Yes, you can use Convert to SM as many times as you want and in NX12 when you get there you have many more options to convert (and convert local areas only).

 

The HD3D tools Frank mentioned were introduced in NX12 so again, check them out when you get there.

 

Dave