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Section Views in Assembly NX10 and NX9

Siemens Builder Siemens Builder
Siemens Builder

Hi Experts!,

recently Customers ask me about how have they proceed to get Drawing Sections Views as show in attached picture(for Nx10 and Nx9).

Futhermore ,they want know about how they have to perform sections view in order to get delete sides pointed in attached image too.

Question related to crosshatching in only part indicated is requested for this kind of sections views.

About using section that you perform in 3d Modeling (View group in Modelling application) in drafting application ..is It an alternative to do this?

 

Thanks in advanced for your help.!

7 REPLIES

Re: Section Views in Assembly NX10 and NX9

Siemens Honored Contributor Siemens Honored Contributor
Siemens Honored Contributor

Take a look at the attached files.  Looks like a lot of this would have to be accomplished using View Dependent Editing.  You can prevent bodies from being sectioned using the Section in View command.VDE_assembly.jpg

Re: Section Views in Assembly NX10 and NX9

Siemens Phenom Siemens Phenom
Siemens Phenom

The non-section of a component can be done in one of two ways.  If you never want to ever section that component irrespective of where it might be used, you can add a Part Attribute to the original part file titled 'SECTION-COMPONENT' with the value set to 'NO'.  The other way is used if you only want to the show a component as not sectioned in some assemblies or even in only some views.  What you want to look for is the 'Section In View' function where you can declare which components are sectioned on non-sectioned and view by view basis.

 

As for the Crosshatch or not, if you don't want one or more of the sectioned components to be crosshatched, simply create the section view and then 'Hide' the crosshatching that you don't want to see.

 

As for the boundaries, you can manually define the boundaries of a Section View just like any other view.

 

Below is a Section view where I've un-sectioned one component (the shaft), Hid the crosshatching from another component (the arm) and then created a custom boundary. 

Edited section view.PNG

John R. Baker, P.E. (ret)
EX-Product 'Evangelist'
Irvine, CA

Re: Section Views in Assembly NX10 and NX9

Siemens Builder Siemens Builder
Siemens Builder

Dear BenBroad,

thank a lot for your reply.....that is the Customer need for their Drawing.

Only one doubt more...how can get 3d sections and put in 2d drawing view?

(see attached image).

They want know how can use sections made in 3d in 2d drawing view.

 

Regards,

Re: Section Views in Assembly NX10 and NX9

Siemens Builder Siemens Builder
Siemens Builder

Dear John R. Baker,

thank a lot for your reply.....that is the Customer need for their Drawing.

Only one doubt more...how can get 3d sections and put in 2d drawing view?

(see attached image).

They want know how can use sections made in 3d in 2d drawing view.

 

Regards,

Re: Section Views in Assembly NX10 and NX9

Siemens Honored Contributor Siemens Honored Contributor
Siemens Honored Contributor

If they have access to the PMI application they could create a PMI section:

 

PMI_section.jpg

I've attached the drawing part only - use the original assembly part files as these were not modified.

Re: Section Views in Assembly NX10 and NX9

Siemens Phenom Siemens Phenom
Siemens Phenom

Actually it can be done in Drafting without the need for PMI, as shown below:

 

Section View with additional curves.PNG

 

This requires that you first add the section curves to the model which can be done using the Clip Section function, extracting the section curves, placing them on a unique layer and then added the view to the Drawing using 'Visible in View' to show the section curves in only one view.  Then you use the 'Pictorial Section View' to create the section view of an Existing view.

 

That should give you enough hints to find what you're looking for.

John R. Baker, P.E. (ret)
EX-Product 'Evangelist'
Irvine, CA

Re: Section Views in Assembly NX10 and NX9

Siemens Honored Contributor Siemens Honored Contributor
Siemens Honored Contributor

Another alternative would be the Break-Out Section in Drafting:

 

Breakout-Section.jpg