I have the name of the tile box with this callout <W@$SH_PART_NAME>. It shows PART VISUALIZATION NAME+(DWG FILE NAME).
By PART VISUALIZATION NAME I mean the text I see for the revision in NX and in TC which is a chain composed by ID+REVISION+VERSION+NAME
By DWG FILE NAME I mean the name TC gives to the dwg file (Specification: ID-REVISION-dwg1).
I would like to avoid DWG FILE NAME to be shown in this field. I can do it by change the <W@$SH_PART_NAME> callout for callouts for ID, REV and NAME but I would like to automaticaly call the PART VISUALIZATION NAME just in case it is changed in future. Is there a way to call it without calling the DWG FILE NAME)?
Solved! Go to Solution.
Thank you Ruud, <W@$SH_MASTER_PART_NAME> worked perfectly.
Is there a list with all available expressions for calling atributtes?
the link below is from the documentation of NX that shows all the default System attributes for drafting
This is the default list.
<W@$SH_SHEET_NUMBER> = Sheet number of the current sheet
<W@$SH_NUMBER_OF_SHEETS> = Number of sheets in the current part
<W@$SH_SHEET_REVISION> = Revision letter of the current sheet
<W@$SH_SHEET_SCALE_NUMERATOR> = Numerator of the sheet scale
<W@$SH_SHEET_SCALE_DENOMINATOR> = Denominator of the sheet scale
<W@$SH_SHEET_SIZE> = Size of the current sheet
<W@$SH_SHEET_UNITS> = Units of the current sheet
<W@$SH_SHEET_PROJECTION_ANGLE> = Projection angle symbol of the current sheet
<W@$SH_MASTER_PART_NAME> = Part name of the master model displayed in the drawing sheet.
<W@$SH_PART_NAME> = Sheet part name
<W@$SH_SHEET_ZONE> = Sheet zone