Hi, All! I'm new to both Siemens NX and to the community. Please bear with me as I refer to all features, procedures and objects by the wrong names, ask interminal dumb questions and generally cause eye-rolling to the point of headaches. I've got a demo copy of NX11 (until the bean counters get off their ***** and write a check)... and my boss has entrusted my green self with the task of creating 4 fairly complex models and 2 REALLY complex models in a month. Lucky me. What I've learned so far is, NX is really hard.
I have a sketch in which I need to trim a line at a datum plane. I can't find a way to project the plane to the sketch, and the trim command doesn't recognize the plane. I can't dimension the endpoint to the plane, either. Is is possible to project a plane in a sketch? Thanx.
Solved! Go to Solution.
A few ways to do this:
1. Use Quick Extend.
2. Use a Geometric Constraint - Point On Curve, endpoint of the line on the plane.
3. Use a Perpendicular Dimension to the Datum Plane.
4. Double click the line, at the bottom of the dialog (make sure it's fully expanded) you should see the curve limits - start and end - change the appropriate limit to Until Selected and then select the Datum Plane.
All of the above work in NX11.0.1.
The datum plane will need to come before the sketch in the feature tree. A feature that comes after the sketch doesn't exist when you are editing the sketch and therefore cannot affect the sketch.
In addition to the above, make sure your Selection Scope is not set to Within Active Sketch Only. You should be able to select almost any geometry outside of a Sketch just like in the attached movie. If you can't then you have something set such that it's preventing it from behaving the way you wish.
If you set your Modeling Preferences under the Edit tab, Double-click Action (Sketches) to Edit With Rollback you won't see features that come after the Sketch when you're in Edit mode. That might present to you a bit more of a clue when you run into timestamp related conundrums like this one.
I've always preferred the Edit with Rollback option when editing things because it can remove potential problem makers.
File, Preferences, Modeling, then the Edit tab.
I'd also change it here:
File, Utilities, Customer Defaults, Modeling, General, Edit