In IDEAS you could use FEATURE COPY to associatively copy features within a part. This was useful when patterning or mirroring wouldn't work. Pro-E has PASTE SPECIAL which if I remember right, does the same thing. NX has PASTE SPECIAL but it's non-associative.
In NX how can you associatively copy a feature like a boss or pocket and place it somewhere else on the part? I tried different things and did some research, but I don't see any easy way to do it?
How is everyone out there handling that?
Thanks in advance,
You can create "User defined feature". With help of it, you can insert boss/pocket/custom feature associatively into other part.
Tools > User Defined Feature.
What I ended up doing is using an associative extraced feature command and then moving the extracted body (using point to point) to a new location point. The body is still associative to the to original, so that is what I'm trying to do, but it is there a cleaner method?
Have you tried looking into pattern geometry, or (Feature)? Set the layout option to general, Then you can copy the geometry from point to point or from a Coordinate system to Coordiante system.
That is exactly what I was looking for! I was able to slap features anywhere I had place points and add features on the back side of the part by adding a CSYS in first!!!
I never knew that general tab was there. I only did linear or circular patterns.
Thank you kind sir!
As a long time Creo (Pro/E) user this is exactly the functionality I was looking for in NX - CSYS to CSYS associative move/copy using Pattern Geometry [General].
In my case I also had to change the orientation in the Orientation section of the dialogue to “Follow Pattern” (default is “Same as Input” - Thanks Glenn!) because I had both linear and rotational offsetting of the destination CSYS.