Custom Shape Springs in Solid Edge Part 2

Phenom
Phenom

...continued from Part 1

 

03.pngHourglass and Barrel Springs

 

Start with a new part  02.png by clicking the Solid Edge Application Button > New > Part.

On the Ribbon bar, take the Tools tab and from the Model group, select Synchronous.

The feature PathFinder updates to reflect this.
Start Line 45.png and hover the mouse over one of the vertical planes - Right (yz) or Front (xz)

 

04.pngWhen the plane highlights, click over the small lock icon as shown in image to lock the plane for sketching.


Draw a vertical line 100 mm beginning from the Origin.
Key-in 100 in the Length box on the Command bar and move the cursor.

 

05.pngA pink line starts appearing as you move the cursor. Move the other end point of the line till you see the vertical alignment indicator as shown circled in image besides. To show such relationship symbols or not is specified in the Intellisketch Options 54.png dialog's Relationships tab found in its group on the ribbon bar.


Click to place the line which is 100 mm and vertical in the xz Base Reference Plane., then click this icon 06.png found on the right side of the screen to unlock or release the sketching plane.

07.pngSimilarly, draw a Rectangle by two Points 19.png in the Top (xy) plane. Key-in the Width as 50, height as 2 and Angle 180. Apply a Smart Dimension 41.png if required. Your sketch should now look as shown on the right. The rectangle can be connected to the origin or away from it leaving some.

 

10.pngFrom the Surfacing tab, Surfaces group, select Swept 08.png
For the Path step, select the vertical line. Click Accept 09.png on the Command bar or right-click or press <ENTER>.

For the Cross Section step, select the rectangle.

Don't Finish the Swept command yet. Click Sweep Options on the Command Bar and in the Twist area, specify Number of turns as 12.

Click OK in the options dialog and Finish the Sweep command. The surface should form as shown.

 

11.pngFrom the feature PathFinder, check OFF the Sweep1 surface to hide it.

From the Sketching tab, Planes group, select Coincident Plane 12.png and select the Top (xy) Base Reference Plane from the PathFinder. A new plane appears with the Steering Wheel active.

 

Drag the vertical primary axis of the steering wheel 50 mm up.

Similarly, create another plane parallel to the last created plane at distance of 50 mm above.

 

13.pngStart Circle 15.png and lock the Top (xy) Base Reference Plane for sketching.

Set the circle diameter to 100 and centered about the Base.

 

On the middle plane, draw a concentric circle of diameter 50 mm.

On the top-most plane draw another concentric circle of diameter 100.
Use Ctrl+T or Ctrl+H 16.png to switch to the Sketch View.

 

17.pngStart BlueSurf 18.pngand select the three circles in proper order to create the BlueSurf as shown below.

Next check ON the Swept surface from the PathFinder to make it visible and start Intersect 21.png from the Modify Surfaces group of the Surfacing tab.

Select the Swept surface and the BlueSurf one after another and click Accept 09.png

 

  20.png

In the Trim and Extend Step, select the two surfaces of the swept surface formed by the far and near sides of the rectangle's shorter side.


You can use the QuickPick 30.pngto choose the surfaces needed. Click Accept 09.png and the resultant trimmed surface should look like as shown in image.

 

Hide the Swept surface again and you should see whatever is left of the the BlueSurf - a thin sliver as seen in image below.

 

23.pngStart Derived Curve 25.png from the Curves group of the Surfacing tab. Pick an edge of the BlueSurf to create the curve.

 

Hide the BlueSurf too and all that is seen is the derived curve - a path for creating a Swept protrusion.

Create a a Plane Normal to Curve 29.png by picking the derived curve first and then one of its endpoints.

 

Create a Circle 15.png in the new plane with its center at the pierce point of the curve with the plane.

 

01.pngFrom the Home tab, Solids 27.png drop button, start Swept Protrusion 28.png and use the derived curve as path and the circle as cross section to create the spring in the shape of an hourglass.

 

The Barell type spring can be similarly created by using smaller circles at the ends and a larger circle in the middle.

 

The idea is to intersect a helical surface with a surface of desired shape of the spring.

 

 

51.png

Creating a Tablet Spring

 

In Tablet springs the coil of wire winds square about the axis instead of a circular fashion.

 

Thus a Tablet spring is square/rectangle shape winded using stainless steel and is mostly used in tablet, capsule blister packing machine in pharmaceutical industries.

 

The tablet spring can also be created using technique similar to the one described above for hourglass spring.

 

This involves using two identical rounded rectangles instead of circles to create the BlueSurf.

 

52.png

To create the tapered tablet spring create a BlueSurf between two rounded squares or rectangles which are of different size as shown besides and intersect it with the helical or twisted surface

 

The other steps remain identical. Again the possibilities are endless.

 

double-conical-spring-250x250.jpg

Look at the double conical spring shown besides. Think how you can model it in Solid Edge using the techniques demonstrated so far.

 

Post below pictures of your creations in the comments area.

Comments
Phenom

Hi,

 

Briliant articles, good jobs! Solid Edge offers many ways to do similar thing like this. For example I don't use Derived Curve or Intersect command.

What I prefer is Intersection curve. Modelhistory will stay simple there is no additional feature.

 

Here is an example (toroid coil):

 

BR,

Phenom

Imi, all I can say is Wow !

The variable table part is especially laudable.

 

Thanks for the video. This is your signature style of communicating - highly appreciated !!

They say a picture is worth a thousand words.

I'd say your videos are worth a thousand bucks - except don't ask me who is going to give you those !! Smiley Tongue

 

This community is already emerging as great place for enhanced learning, be it the forum or blogs.

 

Regards,

Tushar

Phenom

Tushar,

 

Thanks!

We have to build SE community and I think this forum is good for this.

 

Thousand bucks??? Ha-ha-ha. Smiley Wink This is my hobby after my dog. Smiley Very Happy

 

C'mon Solid Edge, Design together!

BR,

 

 

 

 

Pioneer

Great tips, exactly what I needed today. 

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