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Introducing the new ST7 Hole Command

Siemens Genius Siemens Genius
Siemens Genius

New for ST7 we have completely rebuilt the Hole Command user interface and the way hole information is stored.  We’ve also added new functionality to how holes can be modeled.

New User Interface

When you open the Hole Options dialog, one of the first things you notice is that you can now see a graphical representations of the hole parameters.  As you click through the different types of holes, or change the options of the hole, the representation of the hole updates to reflect your selections.  This makes defining the hole you want a more intuitive experience.

The UI still supports the usual hole types of simple, threaded, Counterbore, countersink, and tapered, with the usual options for depth control and bottom treatment.  And you can still apply threads to any type of hole (except tapered).  

New Functionality
In addition to the new user interface, there are a couple of new options available through this dialog – the ability to create start, end (Ordered mode only), and neck chamfers (for Counterbore holes).  With this new capability you can now add chamfers to holes as part of the hole feature itself instead of having to add them as a second feature.

Also new for ST7 is the ability to control what diameter hole is created on the actual solid model when creating threaded holes.  Prior to ST7, threaded holes were always modeled at the Internal Minor Diameter.  Now you have the option to have the hole modeled to the Tap Drill Diameter, Internal Minor Diameter, or the Nominal Diameter.  This can be useful if you have other applications that interrogate the model and are looking for specific diameters to use to identify threaded holes.

Behind the Scenes
Perhaps the most significant change to the Hole functionality is that the hole database files are now in Microsoft Excel format instead of plain text.  Microsoft Excel is not required to be installed for Solid Edge to use the database files, though you will need a separate program such as Excel or Open Office Calc to edit them.

The new format for the database files makes it easier to edit them using standard spreadsheet processing tools.  Sorting, searching, and editing in a familiar spreadsheet environment will make maintaining your hole database files a snap. 

Out of the box, Solid Edge now delivers 7 different database files for the following standards: ANSI Inch, ANSI Metric, DIN, GB, GOST, ISO, JIN, and UNI.  These files include industry-standard holes that you can immediately put to use in your designs.

You can also create and use your own custom database files.  And if you have legacy custom text hole database files, we also provide a utility ( by default, C:\Program Files\Solid Edge ST7\Custom\HoleDatabaseConverter\ ) that will convert them into the new format.

When creating a new hole, most hole parameters will be populated for you based on the kind and size of hole you choose from a standard.  But of course you can always manually override any parameter if desired.  When you do this, the field with the override value will turn yellow to alert you to the fact that you are using a non-database-driven value for that parameter. 

We hope that you find the new Hole interface and databases easy to use and that it provides a faster, more intuitive way to create holes in your designs.

Steven Sheldon

* Opinions are my own


Just got upgraded from ST4 to ST7.

I like the changes to the hole command, but I have a question about using data from it.

 Is it possible to add the chamfer information from a hole to a standard callout?


I have clearance holes which have a small chamfer .030" x 45° on each end of the hole.


Here is my callout:


TYP. (6x)


I'd like to add a line that will call out the chamfer size and angle

Siemens Genius

Hello gpatchel,


Yes, Smart Text is available to display the start and end chamfers of holes.




From the Callout menu, choose the ST (Select Symbols and Values) button.

Expand Values and then Feature References and you will see the list above.


This also works for dimension text similarly.




Thank you Steve.

Excelent info.

I was sure there was a way, just couldn't find it.


Now, is there a way to change the number of places decimal for the callout?

I want it to default to a 3 place decimal, which it is.

However I want the callout for the chamfer to show as a 2 place decimal.

champ callout.JPG


from SE Help:




Where integer n specifies precision format for a property text value that starts with a number.





Spot on.

Thanks Matt.

Great Link.


It would be nice to have an easier function within the callout menu to accomplish this.

5/6 of our engineering dept would struggle to format callout codes.





Solution Partner Valued Contributor

Hello All


Is there a way to open the hole database in a program other that microsoft excel? I mean to change the settings to open the database by default in OpenOffice or LibreOffice?


Any help here would be apprecaited.



Hello guys, 


i am facing a issue with wrong hole size information. I am working on ANSI drawings and they requiered to have a proper naming of hole size. For threads is not a problem to have it based on excel sheet file, BUT with simple holes is it a really trouble and i am not able to have a NAME instead of size. Would any one be so kind and help me out with it? 


Thank you! 





How do I pull (into a drawing callout) the Internal Minor Diameter (or even tap drill size) on a threaded Countersunk Hole?

My reasoning is I want to specify the drill depth [accomplished by using %HD] but I want to show the drill diameter first...note, %HS is showing the nominal thread diameter (from the threaded tab Excel sheet).


Yes I can obviously just type in the drill diameter manually...but the whole point of linking is to prevent any unwanted errors if the nominal size of the countersink is changed.



Apparently the top edge of the countersink was split/cut in two and it mattered which line I chose to attach the callout too...

Siemens Genius

Hi Srypstra,


Here are the callouts I used:









That's awesome...a nice summary for feature reference callouts!

What version are you using?

I'm on ST7 MP0 and %ND, %MD, and %DD do not show anything linked for me.

Siemens Genius

Hi Srypstra,


I do believe this functionality was introduced after ST7.   I will have to research when this happened and get back to you.



Siemens Genius

Hi Srypstra,


The new hole parameters were introduced in ST8.