Copy assembly and links

Phenom
Phenom

Hello,

 

I have assemblies that include assembly created parts. Every part contains links to the asembly I need to maintain.

 

How do I copy the assembly (and rename it) while maintaining the links?

 

Revision manager: Breaks links

Save file as (inside ST6): Breaks links

 

Best solution so far: Copy the Assembly and Parts from one directory to another using windows. Links are maintained until the assembly file is renamed....that kills the links. Because of this, I must assume that the assembly created part files point to the assembly file name and search starting with the same directory. If this is as good as it gets, then I will end up with 100's of files that have the same name and forces me to track files with directory names.

 

Have any figured out how to copy and rename an assembly that maintains links?

13 REPLIES

Re: Copy assembly and links

Valued Contributor
Valued Contributor

Hi 12GAGE

 

I generally use resision manager to copy and rename assemblies with links, usually with reasonable success.  What is it you are trying to achieve?  for example, do you want the new assembly model to use the existing parts that were created in place with links staying with existing assembly from which they were created.  Or have a new assembly with new parts all linked only to the new assembly.

 

Let me know what you are trying to achieve and I will see it that works with my workflow.

 

Mike

Re: Copy assembly and links

Phenom
Phenom

My goal is:

 

To make a copy of a design so that it may be modified seporatly from the origional.

 

The design is a collection of files

The drafting file

The assembly file

The assembly driven parts of the assembly

 

If this were AutoCAD, it would be as simple as "Save as"

But since there are multiple files and links between the assembly and parts. The "copy" process is not intuitive.

 

Also the copied part files don't change name. But the assembly and Drafting file do change names.

 

 

Re: Copy assembly and links

Phenom
Phenom

12 Gauge,

 

The best way to do this is to Open the DRAFT file that contains all the Assemblies and parts in Revision Manager. Then use Copy and save them ALL to a new Folder (path).

 

This of course only works if you have 1 Draft file (even with multiple pages) for an Assembly. But it will capture all the Part and Assembly Files files shown in the Draft on all pages.

 

As discussed in another thread, many folks have numerous pages in their Draft files representing a complete project. While other's need to use a "one single Draft page per part" strategy due to using the same part(s) in multiple assemblies, so this probably wouldn't work.

 

Bob

Re: Copy assembly and links

Phenom
Phenom

Thank you!

 

That's what I needed to know. "Only open the last file in the chain with revision manager". Then all the links can come along for the ride, the files stay associated with each other, and break ties to the origional files.

 

Notes:

I'm running about 20 to 50 pages of 2D PDF per drafting file

I only have two catagories of files/parts:

Standard parts----used by everything that never move or change, referanced by every assembly

Assembly created parts----sheet metal that is controlled by an assembly. Only belongs to a single assembly.

Re: Copy assembly and links

Esteemed Contributor
Esteemed Contributor

So a typical Revision Manager process for moving/renaming or copying complete structures would be:

  1. Open your upper most part of the structure (Main assembly).
  2. Modify the structure as needed.
  3. Select all lines being modified and perform a Where Used.  This gets the drawings and any other SE files that the items in the structure are referenced by.
  4. Update/modify the where used results as needed to copy drawings or update links to prevent broken links.
  5. Perform actions.

Thanks,
Ken

Production: ST9 MP10
Testing: ST10 MP1

Re: Copy assembly and links

Phenom
Phenom

Hello Grundey,

 

Thank you. Respectfully, I disagree.

 

In general, I want to copy files, verify links, rename file, and verify seperation from origional files before I ever start modifying anything.

 

Also, I need to copy all file starting with the drafting file to maintain links between the drafting, assembly and parts all together.

 

Notes:

I'm running about 50 links from parts to assembly, and another 50 from assembly to drafting.

It takes me about a day to create a set of parts, assembly and drafting files.

Im just about to add about another 50 spreadsheet links to all these file to overcome the shortcommings of the packaged "bend tables"

 

 

 

Re: Copy assembly and links

Phenom
Phenom

I need to ask something. When you say "where used" What command are you talking about?

Is this something in the revision manager or the graphic editing/modeling window or the part tree? 

Re: Copy assembly and links

Valued Contributor
Valued Contributor

"Where used" is part of revision manager, found under the "tools" tab.

 

I have found that on large assemblies with many links it is usefull to open the high level assembly and use "Inter-Part Manager" to check for issues with links, image attached.

 

Mike

 

 

Re: Copy assembly and links

Esteemed Contributor
Esteemed Contributor

What do you disagree with? The process I outlined for you will do exactly what you wanted to do...


Thanks,
Ken

Production: ST9 MP10
Testing: ST10 MP1