as I interpree Your picture, it seems for me, that You want to pattern bolts.
So if there is a hole pattern in the part, then You can use it for patterning the bolt in the asm.
thats not really the case ... those bolts will be welded by a CNC welder and there is nothing except some coordinates that marks their position on that plate ... so the only thing I can do is a sketch where I mark with points (or circles) the position of those bolts
so, try it as following:
Even if there are no holes in Your part, creat a hole feature.
But now, detach them.
So You will get a surface hole feature, which doesn't change Your part, but is a valid feature for patterning within the asm
Works fine for me here!
forgot to mention:
this will work in synchronous that way!
Haven't found a way to do similar in traditional
there will be a method for a pattern without a corresponding hole feature.
Create a patternb along a curve witihn Your ASM.
Here You - for a very long time - have the possibility to insert additional accurences on vertex point of Your cure.
If Your "curve" will be a set of straight lines, this is a very simple task then.
no, start with chain selection of Your line set, giving 2 elements for fit.
This brings You one instance at the beginning and one at the end.
And then look for the last icon "Add occurence"
Then You can select every vertex point on Your lines to add additional pattern instances,
which give You for instance a result as following
I've solved this challenge on part level. What does this mean?
You can use Pattern by Table in synch and ordered too. Other solution is what was mention by @hawcad detaching holes, but this works only synch mode.
You have mentioned that you need a solution in ordered mode. Yes, you can do this in it, the key thing is the "multibody" modeling there.
Here is a video and it contains all solutions what was mention by me:
1. Pattern by table (both) 0:00 - 5:44
2. Detach holes (synch) 5:45 - 11:38
3. Multibody modeling by holes (ordered) 11:39 - 16:06
I hope this help!