Saving parts from an assembly to a new sub-assembly

Phenom
Phenom

Is there a way to save some selected parts from a parent assembly to a new sub-assembly but still keep them in the parent assembly ?

I know there is the Transfer command but that moves the parts.

I thought of using Transfer, then closing the parent assembly without saving but I'm not sure that would work.

HP Z420 16GB RAM
Quadro K4000
ST7 MP10 on Windows 7 Pro 64.
5 REPLIES

Re: Saving parts from an assembly to a new sub-assembly

Community Manager Community Manager
Community Manager

Maybe give more context on what you are trying to achieve? It would be pretty odd to push them down to a sub asm and keep them at the top level -- they would all be on top of each other. What is it you are trying to do -- what is the end goal?

Dan Staples
Director, Solid Edge Product Development

Re: Saving parts from an assembly to a new sub-assembly

PLM World Member Genius PLM World Member Genius
PLM World Member Genius

Wonder if the disperse command could do any good for you? I call this option the IKEA kit option. It is like having a bag with components, you drop those out of the bag and start assemble them

 

Assemble parts together...... from the assembly got to SE options, and under Assembly tick Disperce this assembly during Place part

 

«...

Disperse This Assembly During Place Part

Specifies that you want to automatically disperse this assembly when you place it as a subassembly in another assembly. When this option is set for an assembly document, the parts themselves are placed in the assembly, rather than the assembly.

This option is typically used when placing a subassembly that contains a component that is part of a alternate components group. For more information on working with alternate components, see the Define Alternate Components command topic.

...»

 

Restructure assembly

Re: Saving parts from an assembly to a new sub-assembly

Phenom
Phenom

It was another user who asked me if there was a way to do it.

He wanted to do it because he was filtering out parts to pass over for structural analysis - so a new assembly of just the required parts was the easiest way to do it.

He did achieve it by creating a copy of the assembly then repeatedly using the disperse command and deleting the unwanted parts.

 

A command to copy selected parts from different sub-assemblies to a new single sub-assembly would be nice to have.

HP Z420 16GB RAM
Quadro K4000
ST7 MP10 on Windows 7 Pro 64.

Re: Saving parts from an assembly to a new sub-assembly

PLM World Member Genius PLM World Member Genius
PLM World Member Genius

Ok try this

 

Since the information will be used by an external application.

 

  1. Create a display configuration to keep only what you desire
  2. Export using JT file, using the export option:
  • JT assembly, sub-assembly and part
  • Translate visible part only

 

  1. Make sure you save JT files in a specific folder isolate from the original design to avoid same name document contanimation.

 

  1. Then import back to SE If you require SE native file

 

http://www.soliddna.com/SEcommunity/page/articles.html/_/solid-edge-wiki/jtfile

 

If not then save visible parts to any other format that is compatible with other software.

 

Question which structural analysys tool are you suing and what are the file format suppor CIS/2  IFC....

 

 

Re: Saving parts from an assembly to a new sub-assembly

Siemens Genius Siemens Genius
Siemens Genius

If you are on ST5 or newer, you should consider the Insert Assembly Copy command (search in command finder). The command is akin to associative disperse. You create a new "structural_analysis.asm' and Insert Assembly Copy your original assembly into it. You will have the option to include or exclude components that you want to and their position will be associatively maintained as the original changes or new components are added.

 

You can also break the link if you want a once and done.

 

Regards,

Aditya 

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Aditya Gurushankar
Manager, Solid Edge Planning